Parametric Programming in Feature-Based Machining

Abstract

This paper evaluates the feasibility of using parametric programming in the implementation of feature-based machining. Custom Macro B was used in this study. Macro programming technique comprises of a main program and subprograms. NC program for a basic type of machining feature namely pocket was first generated using macro and CAM system. Macro program utilizes very fewer blocks than CAM generated program. The different between both programming methods are discussed. Finally, an integrated feature based machining system is proposed.

Full text

International Journal of Engineering & Technology Sciences (IJETS) 1(4): 218-225, 2013
ISSN 2289-4152
© Academic Research Online Publisher
Research Article
Parametric Programming in Feature-Based Machining
M.A. Razak a,*, M.R. Ibrahim a, S. Sulaiman a, A. Jusoh b, A. Zakaria b
a Manufacturing Section, Universiti Kuala Lumpur Malaysian Spanish Institute, Kedah, Malaysia
b Universiti Kuala Lumpur Institute of Product Design and Manufacturing, Kuala Lumpur, Malaysia
* Corresponding author. Tel.: 604 403 5199; fax: 604 403 5201
E-mail address: alhapis@msi.unikl.edu.my
A b s t r a c t
Keywords:
Parametric programming
Feature-based machining
CNC
Macro
This paper evaluates the feasibility of using parametric programming in the
implementation of feature-based machining. Custom Macro B was used in this
study. Macro programming technique comprises of a main program and
subprograms. NC program for a basic type of machining feature namely pocket
was first generated using macro and CAM system. Macro program utilizes very
fewer blocks than CAM ge
nerated program. The different between both
programming methods are discussed. Finally, an integrated feature based
machining system is proposed.
Accepted:17 July 2013 © Academic Research Online Publisher. All rights reserved.
1. Introduction
Machining feature is the remnant volume after subtracting the designed feature from the raw material
[1, 2, 3, 4]. Rough machining feature is the volume after roughing is subtracted from the raw material.
The machining feature should include the topological and geometric information of the machining
region to offer preliminary data for generating the machining strategy. Examples of machining
features include faces, pockets, holes, and slots.

M.A. Razak et al. / International Journal of Engineering & Technology Sciences (IJETS) 1(4): 218-225,
2013
219 | Page
Fig. 1: Example of machining feature
The machining features used to make a specific part may be instances of a fixed library of
parametrically defined features, or they may be defined without a library by making boundary or
constructive solid geometry representations [5]. There are many alternative definitions of machining
features. To machine a part, both the machining features and the machining operations must be
defined, and the operations must be sequenced. A feature-based machining system strengthening the
function of material removal machine to work in more intelligent and helps the user to shorten the
pre-machining setup time [6]. While a generative process planner enables a computer numerical
control (CNC) machine to automatically define the operations for cutting the designed features [5].
Without machining feature, program is input manually and the cutting path will based on the
coordinate given. Programming will take longer time and the machining efficiency will not achieve as
good as feature-based.
Fig. 2: Feature approaches classification [7]
Feature-based machining can be implemented in three ways as shown in Fig. 2. Design by feature [8]
is a technique by which the designer can document and communicate the design intent. For instance to
define a hole, designer can specify radius, depth and location parameters. The second approach is by
means of pattern recognition. This method is largely used in computer-aided manufacturing (CAM)
software. However generating NC program by commercial CAM software will result in longer part
program besides utilizing a large memory space in CNC machine controller [9]. And the last approach
is by human assisted recognition. Based on human-assisted recognition, this paper aimed in evaluates
the feasibility of using parametric programming in the implementation of feature-based machining.

M.A. Razak et al. / International Journal of Engineering & Technology Sciences (IJETS) 1(4): 218-225,
2013
220 | Page
2. Parametric Programming by Macro
Parametric programming [10] is applied to CNC operations in generating a single CNC program for
parts with similar design, inventing macros for machining custom design features, and developing
subprograms for a group of parts that are not similar in design but require similar machining
operations. Parametric programming can significantly reduce the part programming time and these
applications particularly fit group technology manufacturing in which similar parts are grouped into
part families and then processed by a number of machine tools within a cell or by a single multi-
tasking machining center. Different controller manufacturer provide different version of parametric
programming such as User Task (from Okuma), Q Routine (from Sodick), and Advanced
Programming Language (APL) (from G&L). In Fanuc or Fanuc compliant CNC controller, parametric
programming can be implemented by Custom Macro B.
Macro is very similar to subroutine. The different is that macro enables user to specify arguments and
control the variables [11]. With macros, repetitive cycle can be defined. It may be considered as the
highest level of NC programming [12]. This technique is more powerful and flexible. In the
conventional CNC programming, there is limitation in terms of function of each G-Code. Designed in
separated programs, macros can be called by the main program or other macros using macro number.
Fig. 3 shows the path taken by G&M code interpreter modules [13] which are part of a CNC system
to execute the part program. The conventional G&M codes have to pass through a parser, an executor
and a path generator. Macro program will not go through the normal executor. Macro executor
interprets and executes macro commands included in an NC part program.
Fig. 3: Code interpreter modules [13]
Another advantage of macro is since it is similar to the BASIC language; user can make specific
functions that are not provided by the CNC maker by using macro language.

M.A. Razak et al. / International Journal of Engineering & Technology Sciences (IJETS) 1(4): 218-225,
2013
221 | Page
3. Methodology
Fig. 4 and 5 show the experimental workflow and graphic simulation in CAM. The most commonly
machining feature in tool and die making; pocket was used in this study. Feature was first created in
CAD and its NC program generated by a commercial CAM. NC programs are also generated by
manual programming using macros. Machining simulation was then performed on a CNC milling
machine controller to prove its functionality. The experiment was carried out on Fanuc Robodrill α-
T14ίFse machine with Fanuc Series 31ί-Model-A controller. Different sizes of pockets (width, length
and depth) were studied. Machining parameters such as spindle speeds and feedrates were kept
constant. High speed steel (HSS) straight end mill of 10mm diameter was used for this purpose.
Fig. 4: Experimental workflow
Fig. 5: Graphic simulation in CAM

M.A. Razak et al. / International Journal of Engineering & Technology Sciences (IJETS) 1(4): 218-225,
2013
222 | Page
In macro program, variable numbers represent specific information declared by user or referred to
earlier part programs. For instance, #1 is representing the pocket length and #2 refers to pocket width.
To generate a new program for different design, the user needs only to redefine the variables in the
macro. As there is no new program added, the memory used in the controller remains more or less
constant.
There are main program and macro program in macro approach. The main program prompts user to
select the type of feature required. Once selected, user is requested to key in details of the feature.
These include its center location, pocket length, depth, corner radius, depth and width of each cut, tool
number, cutting feedrate and spindle speed. The different between macro and CAM generated NC
programs are discussed in the next section.
3. Results and Discussion
a) CAM generated NC program b) Macro program
Fig. 6: Different between CAM generated and macro program
In the conventional CNC part program, G-Codes are used for specific functions. For example, modal
G codes such as G1, G2 and G3 are for linear interpolation, clockwise interpolation and counter-
clockwise interpolation respectively while the canned cycle like G81 is for drilling a hole. The same
codes may be used repeatedly in order to create or to cut a given machining feature. This technique is
applied in CAM to generate NC program as shown in Fig. 6 (a). Therefore, the size of NC programs
generated by commercial CAM system is usually very large. When using parametric programming,
N126 G1 Z69.025
N128 X-5.
N130 Y-120.
N132 X5.
N134 Y-110.
N136 Z79.025
N138 G0 Z80.
N140 X2.5 Y-112.5
N142 Z79.025
N144 G1 Z68.05
N146 X-2.5
N148 Y-117.5
N150 X2.5
N152 Y-112.5
N154 Z78.05
N156 G0 Z80.
N158 X5. Y-110.
N160 Z79.025
N162 G1 Z68.05
N164 X-5.
N166 Y-120.
N168 X5.
N170 Y-110.
N172 Z78.05
WHILE[#118LT[#111-#117-#23]]DO1
#118=[#118+#10]
IF[#118GE[#111-#117-#23]]THEN
#118=[#111-#117-#23]
Y[#102-[#112-#117-#23]]
X[#101-[#118-#23]]
Y[#102+[#112-#117-#23]]
X[#101+[#118-#23]]
Y[#102-[#112-#117-#23]]
X#101
END1

M.A. Razak et al. / International Journal of Engineering & Technology Sciences (IJETS) 1(4): 218-225,
2013
223 | Page
the routines can be written as simple as shown in Fig. 6 (b) and makes it much shorter compared to
CAM.
With CAM, the part program can be thousands of blocks in size. It happened because of CAM
generates the program based on cutting path coordinate. The larger the machining part, the longer the
part program. Also the deeper the cutting depth, the larger the program sizes. On the contrary, the
macro program size for the same feature can be constant for different sizes. This is due to the fact that
the size changes can be done by simply redefining the feature variables. These variables are defined
once only but their values can be changed according to the feature. If redefined in main program, the
new arguments will be used by the called macros. Fig. 7 (a) shows macro call program for a pocket.
a) Macro call for rectangular pocket
b) Pocket macro (in machine memory)
Fig. 7: Macro program for pocket
The block “G65P0147X#24Y#25A#1B#2C#3D#7U#21 F#109W#23T#20” can be translated as call a
pocket macro from memory O0147 with the parameters X, Y, A, B, D, U, F, W, and T. Therefore for
a new pocket feature, user needs only to change these parameters. The pocket macro in Fig. 7 (b) is
not visible to the user. It stored in machine memory.
……
G65P0147X#24Y#25A#1B#2C#3D#7U#21F#109W#23T#20
……
O0147 (RECTANGULAR POCKET)
N100G0G90X#101Y#102Z5.(POCKET CENTER LOCATION)
G1Z[#510-#12]F#9
N200WHILE[#118LT[#111-#117-#23]]DO1(COND_DO
POCKET)
#118=[#118+#10]
IF[#118GE[#111-#117-#23]]THEN#118=[#111-#117-
#23]
Y[#102-[#112-#117-#23]]
X[#101-[#118-#23]]
Y[#102+[#112-#117-#23]]
X[#101+[#118-#23]]
Y[#102-[#112-#117-#23]]
X#101
END1
N250IF[#12GE#3]GOTO300(COMPLETE Z ROUGH)
#12=[#12+#21]
IF[#12GE#3]THEN#12=#3(COMPLETE Z ROUGH)
#118=0(START NEW POCKET CYCLE WITH NEW DEPTH)
GOTO100
N300IF[#23EQ0]GOTO400
G1X[#101-[#111-#117]]Y[#102-[#112-
#117]](FINISHING)
Y[#102+[#112-#117]]
X[#101+[#111-#117]]
Y[#102-[#112-#117]]
X[#101-[#111-#117]]
M99

M.A. Razak et al. / International Journal of Engineering & Technology Sciences (IJETS) 1(4): 218-225,
2013
224 | Page
Fig. 8: Simulation on CNC controller
Unlike macro, CAM software will generate a new program for the same feature although there are
minute changes in its parameters. This is where the user can apply macros as alternative. By
controlling the variables, no more programs to generate for the same feature. Unfortunately many
CNC machines come with a limited working memory. Consequently for a machine without a DNC
facility, transferring a new part program is difficult without first deleting some old programs.
Other advantage of macro is that, users are allowed to create their own canned cycles, automatic
determination of feedrate and spindle speed, and creation of new alarms other than that provided by
the controller manufacturer. These all are can easily be done by macros. However, few CNC users are
aware about the existence of macro and know how to create macro program. In fact, people in
industries are continuing the same daily routine with using CAM to generate NC program. This is
mainly because of creating macro program requires individual programming skills and hence users are
often eschew this task. The good news is currently there are softwares available in the market to
simulate limited capability of macro program.
4. Conclusions
From the result, it is confirmed that parametric programming can be used in the implementation of
feature-based machining. For a given feature, commercial CAM system generates large program
blocks hence there is an increase in program memory. With the macro approach however, one can
expect comparatively much smaller program size. Consequently, in practice the old files need no
longer to be deleted very frequently before transferring new programs. Although this could be the
main advantage of macro program over conventional CAM system, further analysis is required
particularly in terms of surface finish, machining time or even ease of programming. Finally, it is
envisaged that an integrated feature based machining system can be realized by having macro
programs integrated GUI (graphical user interface). Hence a post processor is no longer required for
NC program generation.

M.A. Razak et al. / International Journal of Engineering & Technology Sciences (IJETS) 1(4): 218-225,
2013
225 | Page
References
[1] E.Y. Heo, D.W Kim, J.Y Lee, C.S. Lee, F.F. Chen. High Speed Pocket Milling Planning by
Feature-Based Machining Area Partitioning. Robotics and Computer-Integrated Manufacturing,
2011; 27:706–713.
[2] A. Cardone, S.K. Gupta, A. Deshmukh, M. Karnik. Machining Feature-based Similarity
Assessment Algorithms for Prismatic Machined Parts. Computer-Aided Design 2006; 38:954–972.
[3] X. Xu, S. Hinduja. Recognition of Rough Machining Features in 2.5D Components. Computer-
Aided Design, 1998; 30:503–516.
[4] Y.J. Tseng. Fixturing Design Analysis for Successive Feature-based Machining. Computers in
Industry, 1999; 38:249–262.
[5] Kramer, Thomas R. Submitted to National Institute of Standards and Technology, United State of
America 1987.
[6] M. Razak, A. Zakaria. Review on the Evolutions of CNC Programming Methods. 2nd Colloquium
on Manufacturing Technology, Kulim 2010.
[7] A. Mokhtar, A.T. Bina, M. Houshmand. Approaches and Challenges in Machining Feature-Based
Process Planning. 4th International Conference on Digital Enterprise Technology 2007, London.
[8] S. Venkataraman. Integration of Design by Features and Feature Recognition. Arizona State
University, Arizona 2000.
[9] M. Razak, A. Zakaria. A Framework for a Feature Based Machining using Macro. Applied
Mechanics and Materials Journal, 2012; 110:1711–1715.
[10] M. Djassemi. A Parametric Programming Technique for Efficient CNC Machining Operations.
Computer and Industrial Engineering, 1998; 35:33–36.
[11] User's Manual. Common to Lathe System/Machining Center System. Fanuc series
30i/300i/300is-Model A, Vol. 1-3.
[12] M. Razak, A. Jusoh, A. Zakaria. Feature-Based Machining Using Macro. International
Conference on Machine Design and Manufacturing Engineering, Paris 2012.
[13] S.H. Suh, S.K. Kang, D.H. Chung, Ian S. Theory and Design of CNC Systems. Springer Series in
Advanced Manufacturing, 2008; 82–93.